Rotate Body 90 Degrees

How can I rotate the section in blue 90 degrees? Is there a way I can rotate from the center? See picture below. I've also added the part file.

SolidworksParts And Features
Answers 9
AB
AB 2018-01-18 Best Answer

You could cut the part into 2 pieces and then use the Body Move/Copy/Rotate feature to rotate the body with the blue section 90 degrees around its center axis. Then combine them back into 1 piece.

PR
PR 2018-01-18

Simple answer yes.

Split the part into 2 bodies, (make a minimal cut that leaves you with 2 bodies). Move the body with the flat and the whole, fill back in what you cut and you have your part.

KM
KM 2018-01-18

Hi Russell,

You can split the part using a plane parallel to the front (or the front plane itself).

Then use move/copy body to rotate about the axis of the part 90* on just the half of the split that needs rotating.

You can then use combine to put back together as one solid body.

Thanks, Kyle

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RW
RW 2018-01-18

Thanks that was easy..... LOL

GS
GS 2018-01-18

At this point the options given by Paul and Alex would probably be the simplest.  Another option would be to edit the sketch planes that created those cuts, choosing one that's perpendicular to the current one.  However, that's going to throw up some sketch errors.  Fixing them might be good practice if you want to try it and aren't in a big hurry.

RE
RE 2018-01-18

Hi Russell

MoveFace is pretty cool!

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RW
RW 2018-01-18

That's Great !!!

MD
MD 2018-01-18

I agree with this approach.  The way the "correct" answer proposes seems to me like a hack job and will probably add unnecessary complexity to your feature tree.  What I would do is try to change the planes the cuts/holes are on and if that doesn't fix it satisfactorily, then just remake the part.  Good practice anyway, easy part to remake.

PR
PR 2018-01-18
<p>Marcus Dimarco wrote:</p><p></p><p>I agree with this approach. The way the "correct" answer proposes seems to me like a hack job and will probably add unnecessary complexity to your feature tree. What I would do is try to change the planes the cuts/holes are on and if that doesn't fix it satisfactorily, then just remake the part. Good practice anyway, easy part to remake.</p>

While I can understand and see yours and anyone else's opinion as I would re-align planes and what no for this part. The question was asked how do I rotate the part itself which is the one I answered.

As far as a tree and it's history and making a part complicated there are a million things that do that, I would not imply that I  know of every circumstance in which the technique I showed above would be applied.

I laud ​ his response below because it is creative and will get the job done in fewer steps for this part.

However my answer was more for the scope of the question rather than the part itself.

This is a moldmakers model of a boat hull that we tooled post processes for. In other words this is the negative solid of a molded part that is just a dumb solid(As the mold was made to, not what the finished part actually was) . The red and purple planes are the A & B datums. All mounting surfaces were to be machined and all holes to be machined to these planar controls. In order to do that we had to move all surfaces to their real time position after mold which meant alot of what I described above of re-aligning surfaces. Since there were no planes, no hole features or any inherent data it was move the solid bodies 2/10 of a degree here 1 degree there, create a new axis for the molded hole now create a reference axis for the machined hole.

So as to whether or not my answer is a viable solution for the specific part in hand maybe, maybe not. I personally like Rob's answer better for this one. It is however based on extensive use of the feature exactly as  I described it and it work in some pretty complex situations where there is no other readily available solution.

If the OP wants to mark Rob's answer as the correct and cleanest one for what he needed I would take no offense.

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