We edit a number of older drawings and we have a external drafting standards file that we load. Is there a way to update the drafting standards of the drawing file without changing the precision of all the dimensions? I'm running 2013 SP5
SolidworksDrawings And Detailing
I would create another Drafting Standard that wouldn't have those precision's and load that..
How do I save a Drafting Standard without the dimension precision?
Change your settings here
Save the Changes
Then Load the changed Drafting Standard as needed
I believe the problem is that when he changes the drafting standard it changes the number of decimal places from say two places to three or vice versa. I too had this problem and could not figure a way around it other then to fix them all manually.
Chris
Sorry, I didn't ask the question correctly.
I am under the impression that I cannot exclude any of the active document settings when I save a Drafting Standard file. Is it possible to pick and choose what settings are saved in the file?
Quick question - are you wanting to change the precision to all dimensions?
No. I want to maintain the existing precision of all drawing dimensions.
Ok - so what do you want to change?
Ahhhh....so if you have 2 drawings, say 1 with .0000 precision and another with .000 precision, you want to be able to change the drafting standard in those drawing without affecting the current setting for precision. Is that right?
If that is right, then I would do this:
Open a new drawing/part whatever, change the settings the way you want and then save the drafting standard as normal....however, change the precision to .00 and then save that drafting standard as ASME_00.
Then change the precision to .000 and save that drafting standard as ASME_000.
Then change the precision to .0000 and save that drafting standard as ASME_0000.
and so on....
Then as you run into prints with different precisions, load the correct drafting standard.
Dan, thank you for your reply.
I have many dimensions on the drawings that might have 1, 2, or 3 decimal places. I don't want to change any of these.
I feel that there is no way to pick and choose the standards that are saved/loaded in the "sldstd" file. It would be interesting to have a macro pull the existing settings, then individual settings could be hacked out.
If that's the case it's all manual from there, unless the API gurus could help.
I'd take a shot and post this question in the API section and possibly post some pictures of the different examples, so that you get some interest and answers..
Wait a minute....
Changing the drafting standard should ONLY affect the precision of the dimensions that are marked with the (Document) Precision:
If they are set to anything else, then the drafting standard shouldn't be affecting the precision of those dimensions (unless it is changing them from fractional to decimal for example).
Did you test it?
Yes, on SW 2015 SP5.....changing the drafting standard affects the precision of all the dimensions that are set to "Document". But NOT the precision of all the dimensions set otherwise.
Not sure about SW 2013. Sorry Dave.
Excellent!! So the way to fix this is to move all the dimensions OFF of the "Document" setting.
Thank you!! I'll look into a macro might change that setting.
Or just make sure that your drafting standard that you are loading has the same dimension precision as the one you are replacing.
Edit: Although now that I am thinking about it, it is possible that the old document standard has precision settings for angular/ordinate/hole callout/etc. that are all different.
Maybe the way you mentioned is the way to go.
I have many dimensions on the drawings that might have 1, 2, or 3 decimal places.
Sounds about right, but a nice shortcut is that you can select multiple dimensions (box around them) and change their settings at the same time
This macro removes the document driven setting from a dimension. It works for all dimensions except for ordinate. At this time, it only checks the primary precision of the dimension. I will be working on the dual dimension value, primary tolerance value, and alternate tolerance value in the next few days.
Operations:
All ideas and thoughts are appreciated.
Here's a better version.
This will check all the settings for each individual dimension before making changes. It also changes dual dimension value, primary tolerance value, and alternate tolerance value.
After this macro has been run, a different drawing standards file can be loaded WITHOUT changing any existing dimension precision.
Awesome that you got it to work!