How do i scale surfaces?

How do i scale surfaces? I have made a rough "skeleton" of extruded boss and bases and made cosmetic features via boundary surfaces and fill surfaces. I've knitted them together to mirror the part and then i noticed i made it too big. Is there any way to scale the surfaces? I have tried using the scale tool and scale about centroid and origin but this only scales the extruded features.

Thanks in advance.

SolidworksParts And Features
Answers 6
DG
DG 2015-09-25 Best Answer

You can knot them into solid and then scale.

OR

You can use offset surfaces/face and then can extend, join/knit them.

SF
SF 2015-09-25

I am afraid your solution doesn't work, or that i don't understand it quite.

This is my shape. As you can see it consists of extrusions and surfaces. What i want to do is shrink it, which doesnt work the way i did it atleast.

Your first solution i supposed you meant knit and tried to knit them together completely into one part with the tool surface knit but and it didnt work when i scaled it. I see that there are several options in the knit tool and i do not understand what each of them do. Which one am i supposed to go with?

The second solution didn't work either since i wish to shrink my part, not enlargen it.

The offset feature did create a somewhat scaled feature, but it was in the end too big.

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JR
JR 2015-09-25

After you knit the surface the surface body needs to become a solid body to be able to use the scale feature. There is a option or setting inside of the knit surface feature to make solid from surfaces or worded close to that.

Then you can do an off-set surface, value to zero, and select all of surfaces of the solid body to have a surface body of the new scaled down item. Or a simpler or less involved way would be to use the delete face feature (choose delete face, do not choose delete and patch) and delete the most simple surface on the part. This turns the solid body into a surface body, that si missing one surface that you just deleted. Now use the filled surface feature to fill in this surface area. Result is a surface body scaled down in size.

SF
SF 2015-09-25

Thank you very much! You just saved me hours of work.

JR
JR 2015-09-25

That was Deepak's post, explained a little differently, and what I would have said if he hadn't posted his solution. I don't use the scale feature often at all but this is if it only works on solid bodies. If you're able to knit all of your surfaces into 1 surface body, then I'd think the scale feature should still work towards the surface body. If the scale feature only works for a solid body, then that's a limitation.

AT
AT 2019-04-08

I'm not sure if it was not always true, but certainly since SW2012, there has been no need to solidify surfaces to scale them:

all you need to do is pick the desired surface bodies (from the folder) when setting the scope of the "Scale" feature.

It is important to pick "Scale About: ORIGIN". This is because with the centroid option, each surface gets scaled about its own centroid.

NEW TOPIC: It can be useful to create reference planes using surfaces instead of planes, for situations where parts will be scaled, as in metal casting.

If planes are used, they will be mislocated after the Scale feature.

Coordinate systems, like planes, cannot be picked when setting the scope of the "Scale" feature, so surfaces definitely seem to be the answer.