How do i make threaded holes on a helical cut surface on a cylinder.

I am unable to make the threaded holes. I was able to make the holes but could not thread them.The error i got is that "The selected entity is not perpendicular to the thread axis".I get that the holes are not perpendicular to the axis how do i make them perpendicular?I have attached the Solidworks file I made .

Solidworks3d Contentcentral
Answers 5
DL
DL 2021-04-08 Best Answer

1. Are you trying to model a physical thread?  If yes, why?

2.  Adding a Cosmetic Thread to Cut-Extrude2 works fine and then gets patterned automatically:

3.  How come you used a Cut-Extrude for the hole rather than using the Hole Wizard?  As the threading details would have been automatically added.

4.  The drawing calls out an M8 tapped hole, but you've made your cut diameter 8mm.  The ID for an M8 thread is 6.8mm (which if you'd used the Hole Wizard, would have been generated).

comment imagecomment image
TK
TK 2021-04-08

Thanks a lot man.

DL
DL 2021-04-08

See attached part.

I've created an additional plane (Plane8) that is 20mm from the end face of the large diameter section.  On this plane, I have created a sketch that includes the maximum OD (as that is where the hole dimensions are specified to start from).  Next, I've created the L-shape sketch entities (highlighted).  You'll see these are located using Pierce points to the edges of the swept cutout;

Then, I created the line that is perpendicular to the base of the "L" and is then coincident with the OD.  This is effectively the axis of the hole, it's centred and perpendicular to the helical face.

Next, Plane9 is made using this last created line and the point coincident with the OD.

A Hole Wizard feature can then be created on Plane9, using the sketch point as the position for the hole.

As John says, you can then use the curve driven pattern for the rest of the entities, then do a Circular Pattern about the parts major axis to do the tapped holes on the other side.

Quick note on your model, there are a few under-constrained sketches (e.g. Sketch1) that may trip you up further down the line.

comment imagecomment imagecomment imagecomment imagecomment imagecomment imagecomment imagecomment image
TK
TK 2021-04-08

How do I centre the holes on the helical surface.

JS
JS 2021-04-08

 

Use the Hole Wizard to make the Threaded hole and then use a Curve Driven Pattern to pattern the threaded hole

comment imagecomment image