Curve Driven Pattern

Is there any way to do a curve driven pattern using a degree instead of an arc length between instances? For example, I have a a 9deg. arc and I want 18 holes equally spaced along it. 

SolidworksParts And Features
Answers 8
SM
SM 2010-11-24 Best Answer

Jacob,

Is this what you are looking for?

KL
KL 2010-11-24

Doesn't the Equal Spacing option give you what you need?

EDIT: If the driving sketch is an arc, you could also use the Circular Pattern to have the angle option.

SF
SF 2010-11-24

I tried that, but my arc is a 3d sketch that uses points on three different planes and each point is at a different radius, so the circular pattern feature doesnt see the arc that i am trying to use as a valid point to array around, because it isnt really a true circle. I also tried drawing an arc in a sketch and using that as my path, but I am trying to make this part update when I change parameters and when i change my parametes it throws my arc out in space and gives me an error.

KL
KL 2010-11-25
<p>jacob may wrote:</p><p></p><p>I tried that, but my arc is a 3d sketch that uses points on three different planes and each point is at a different radius, so the circular pattern feature doesnt see the arc that i am trying to use as a valid point to array around, because it isnt really a true circle. </p>

If you used the 3 Point Arc tool to create the arc, it will be a true arc ... part of a true circle.

The 3 points can also be used to create a plane, on which the arc can be drawn as a 2D arc.

That plane and the centre of the 3 Point Arc could also be used to create an axis ... which in turn could be used in the Circular Pattern.

If you used a Spline to connect the 3 points, you are stuck with the Curve Driven Pattern and Equal Spacing option.

If you used something other than the above, you may have to post the file for review.

The file would also help explain the "parameters" problem.

SF
SF 2010-11-25

If it isn't a true circle, how can you define an arc angle?

One workaround would be to do it all manually - draw your main path. Then draw an arc and make it coincident to the path at 3 points to define it. Then give the arc an angle. Repeat for each instance (hope you don't have too many instances).

SF
SF 2010-11-29

I went ahead and created a plane using my three points and used a 2D 3 point arc, but I cannot put my finger on how to use the center of my circle and the plane to create an axis. I keep getting an axis on the mid point of my arc. I have attached a copy of my part so you have a better idea of what I am dealing with. Thanks

SF
SF 2010-11-29

I had to sketch a couple new arcs to get my center points, but it worked great. I appreciate you helping me with this. Thanks

KL
KL 2010-11-29

To create the axis;

Insert > Reference Geometry > Axis

Select the plane

Hover the cursor over the arc till the Center icon appears

Select the center point of the arc (not the arc itself)