Curve Driven Pattern Problem

I am trying to create a wire loom by patterning an extrudedcut along a loft using the same 3D spline used as the centerline tocreate the loft. I want the pattern to be tangent to the curveinstead of aligned to the seed as shown in the attached picture,but I don't know what to use for the Face normal. When I firstcreated the pattern it worked without me picking anything but assoon as I modify the 3D spline the pattern reverts back to align toseed and requires a Face normal. Any help would beappreciated.SolidworksParts And Features
Answers 11
CC
CC 2009-03-20 Best Answer
You will get much better results (and a quicker rebuild time)if you use body pattern instead of feature pattern, without mergingresults. The drawback is that it will then be a whole bunch ofmulti-bodies. For a wire loom this should be an issue...

Just model one "segment" of the wire loom, and then use a sketchbased pattern, and pattern the body.
SF
SF 2009-04-16
Hello,

I have the same exact problem (my model is in pic1). I am using a3D sketch with lines, arcs and splines. I try the curve patternwith body pattern and not feature pattern option (the body is anextruded cylinder with no merge result option). If I select as acurve a straight line or an arc, I can choose the "tangent tocurve" option and everything goes fine (pic2). But if I choose anspline as a curve, the "tangent to curve" option is not working andI cannot proceed (pic3).

Please can anyone give me a clue in this?
DG
DG 2009-04-16
Create a plane normal to any end of the spline/ 3d sketch,Create you feature on that plane and use Curve Driven Pattern. Youcan select the option " Tangent to Curve".
SF
SF 2009-04-17

George,

It's because it needs the surface to calculate the normal for thetangent to curve option.

Try this: create your 3D sketch of arc and lines. Now do a Fitspline over all of them (Tools>Spline Tools>fit spline)

Now create a Plane at the end of your 3D sketch spline like Deepakhas described, and on that plane create your extrude feature body.

Now create a simple one line sketch on that same plane and that oneend o fthe line is coincident to the end of your 3D sketch and useit to sweep a simple reference surface along your 3d sketch.

Now you can do your curve driven pattern using your extude, yourfit spline 3D sketch and then use the ref surface for the "FaceNormal" and tangent curve option.

See attached.
SF
SF 2009-04-20

Mark Biasotti wrote:

 

It's because it needs the surface to calculate the normal forthe tangent to curve option.
Try this: create your 3D sketch of arc and lines. Now do a Fitspline over all of them (Tools>Spline Tools>fit spline)
Now create a Plane at the end of your 3D sketch spline like Deepakhas described, and on that plane create your extrude feature body.
Now create a simple one line sketch on that same plane and that oneend o fthe line is coincident to the end of your 3D sketch and useit to sweep a simple reference surface along your 3d sketch.
Now you can do your curve driven pattern using your extude, yourfit spline 3D sketch and then use the ref surface for the "FaceNormal" and tangent curve option.

Sorry Mark if I write here,I know it's not the right place,but there is a competition against Inventor that disturbs me.
My VAR can't support me because I'm participating an Italian forumwhere you can find all CAD and the competition is always very high.
I need to simulate the chain and sprockets.
I attached the file to understand better.
I would like just suggestions to avoid follow wrong paths alreadybeginning.
I chose the curve driven pattern to avoid adding lots of mates, butdoesn't work, just move the chain, It jumps all over.
I'm sure that I wrong, because the curve driven pattern computesthe relative position of the object and not adjusting when itmoves, there should be its function in the assembly environment.
Do I have to insert the chain at the top level assembly ?
Path mate it's the best or I've to do as Rachayl Duker suggesthere?
What do you suggest me to do a good simulation ?

Thank you
SF
SF 2009-04-21
Thank you guys.

I've done it like the Mark's example. It's ok now

Thanks again
SF
SF 2016-05-18

Hi Mark

I have the same problem. The file is attached. I want the fins to be normal with curvy pipe. I work on the formula you told. I go to curve driven path->Tangent to curve but i wouldn't select "surface sweep" as face normal.

I would really appreciate you if you resolve this problem

PS
PS 2016-05-18

..maybe this can help you.. at the assembly level, they are patterns driven by features from each component..

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SF
SF 2016-05-19

Thanks, that's what i want. Could you please share the assembly file? i would really appreciate

DG
DG 2016-05-19

He has already added the file. Make sure you're not viewing in inbox else attachment won't show.

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SF
SF 2016-05-19

Got it Deepak. Thanks