Cabling in lighting assemblies

Has any a quick and effective way of adding small cables (approx 2mm) into assemblies, I have a client who I design light fittings for who wants to see the cables in the assemblies, theres alot of different products so being able to quickly draft or drop editable stock cad parts in would be better. Is it a case of 3d sketch in assembly?

All suggestions welcome

SolidworksAssemblies
Answers 4
GS
GS 2013-10-08 Best Answer

A virtual part in your assembly, with a sweep along a 3d sketch, would be one option.  You could have one virtual part containing all of the cables, or seperate parts for each one.

KP
KP 2013-10-08

Thanks for the reply..... a virtual part, never used this before, will look into it. Thanks again

GS
GS 2013-10-08

If this is something you'll be doing fairly often I would strongly suggest creating a library feature part (.sldlfp file) of each cable profile that you need.  Then you can use the Structural Shape function on the Weldments toolbar to create the cables.  You can select the size profile in the FeatureManager, and you can select your 3d sketch from the tree for the path so you don't need to select each line or arc individually.  That will take a little time to set up but it will save a lot of time in the long run.  No need to create a new profile sketch for each sweep.

I often have cables in assemblies, and I use Virtual Components and Structural Shape to create them.  Works well.

The Structural Shape function is also pretty handy for me when I'm creating bent rebar to go in concrete.

EB
EB 2013-10-08

Kathryn,

One caveat about weldments.  They will not work with splines, which I would imagine you will want to use at least sometimes.  I use virtual components to place hoses in assemblies and the method I use is to make a "base part" (or assembly if it has fittings on the ends) which consists of a simple sweep of the hose (or for you wire) profile.  For the path I use a 3D sketch. Start at the origin with a short line along a default axis (X, Y or Z) then a spline with one or two control points then another line (not on an axis) on the end. Make the spline tangent to both lines.  Make a base for each wire type you will need.

When you need a wire in your assembly, insert the base part and locate it using the default planes and/or origin.  Now make the part virtual by RMB it in the feature tree and select "Make Virtual". Now you can edit the 3D sketch and place the "wire" where it needs to be. I usually locate the short line at the end of the spline first and fix it with appropriate relations, then add control points to the spline (if required, the fewer the better) and position it.  You can also add add line segments and more splines or delete the spline and just use lines and arcs.