Grooves on dome like feature

Hello,

I am working on a bottle and can not figure out a way to putgrooves an a panel that is shaped like a dome. I have created ajpeg of the old drawing. You can get a good idea what it suppose tolike in Detail "A", Section "A" - "A", Section "B" - "B". In Detail"A" is what I have been trying to create with no luck. I only needthe grooves to be on the surface of the panel, not in two differntdirections as Detail "A" depicts.

I also have a radius error. If the first one is fixed the secondshould get automatically fixed. My boss is on my case, so I have tosend this out as is. I appreciate any help! Thank, RickSolidworksSurfacing
Comments 7
MA
MA 2008-06-04
I'm not sure of a good way to add uniform grid of v-groovesto a preexisting dome shaped loft. However, I can think of a coupleways to design one from the outset.

1) Create the same features on a flat surface using a patternedcut-sweep. Then use a Freeform feature to deform it into somethingdome-like.

2) Instead of using 3 single-line cross-section sketches for yourloft, use two identical zigzag sketches and guide curves thatinfluence the shape into a dome.
SF
SF 2008-06-04
Rick,

I would be inclined to revolve a single V shape or a few V shapes,then circular pattern the body in the other direction. Make yourfirst body a bit larger than necessary, then trim it to fit.Assuming that your walls are pretty much uniform, I would probablybuild the part with surfaces, then thicken when I had the outsideshape completed.
SF
SF 2008-06-04
Rick,

Like Mahir suggested, create your cut/protrusion v grooves on aflatten surface. Then you can use deform (free form only works on asingle face) with the push option. (See Atttached)

create a planar surface from edges of inset
Replace domed face for planar face just created
did the v groove cuts and protrusions and patterned
Created a tool body to put the dome back into the vgroove area
Insert>Deform>Push>Surface Push and use the tool body withthe appropiate options.

Getting past the sheller is another matter and I haven't tried.

BTW, this looks like a symmetrical part - only model half of it andsave yourself a lot of work, time and it will also be more robustmodel.

Hope this helps
RS
RS 2008-06-05
Create an offset surface that represents the bottom of thegroove. Project the groove centerlines onto the offset surface. Usethe projected lines to create sweep surfaces. Trim and cap sweepsas needed and use for cut w/ surface.
SF
SF 2008-06-07
Roland, I agree that this would be the proper way to do it.My suggestion of using deform was to try to save a lot of tedeouswork given there are 30 curves and sweeps to create (although youcould get clever with a zig zag projected curve then sweep and thentrim back etc.)

RS
RS 2008-06-07
I've done some monster detailed projects like this in thepast. One of the greatest assets for this kind of work is a hightolerance for tedium. Don't focus on how many times each featureneeds to be repeated or think about how boring it is. Just doit.
SF
SF 2008-06-08
Mark Biasotti 's solution is great.