Hello,
I am working on a bottle and can not figure out a way to putgrooves an a panel that is shaped like a dome. I have created ajpeg of the old drawing. You can get a good idea what it suppose tolike in Detail "A", Section "A" - "A", Section "B" - "B". In Detail"A" is what I have been trying to create with no luck. I only needthe grooves to be on the surface of the panel, not in two differntdirections as Detail "A" depicts.
I also have a radius error. If the first one is fixed the secondshould get automatically fixed. My boss is on my case, so I have tosend this out as is. I appreciate any help! Thank, RickSolidworksSurfacing

I am working on a bottle and can not figure out a way to putgrooves an a panel that is shaped like a dome. I have created ajpeg of the old drawing. You can get a good idea what it suppose tolike in Detail "A", Section "A" - "A", Section "B" - "B". In Detail"A" is what I have been trying to create with no luck. I only needthe grooves to be on the surface of the panel, not in two differntdirections as Detail "A" depicts.
I also have a radius error. If the first one is fixed the secondshould get automatically fixed. My boss is on my case, so I have tosend this out as is. I appreciate any help! Thank, RickSolidworksSurfacing

1) Create the same features on a flat surface using a patternedcut-sweep. Then use a Freeform feature to deform it into somethingdome-like.
2) Instead of using 3 single-line cross-section sketches for yourloft, use two identical zigzag sketches and guide curves thatinfluence the shape into a dome.
I would be inclined to revolve a single V shape or a few V shapes,then circular pattern the body in the other direction. Make yourfirst body a bit larger than necessary, then trim it to fit.Assuming that your walls are pretty much uniform, I would probablybuild the part with surfaces, then thicken when I had the outsideshape completed.
Like Mahir suggested, create your cut/protrusion v grooves on aflatten surface. Then you can use deform (free form only works on asingle face) with the push option. (See Atttached)
create a planar surface from edges of inset
Replace domed face for planar face just created
did the v groove cuts and protrusions and patterned
Created a tool body to put the dome back into the vgroove area
Insert>Deform>Push>Surface Push and use the tool body withthe appropiate options.
Getting past the sheller is another matter and I haven't tried.
BTW, this looks like a symmetrical part - only model half of it andsave yourself a lot of work, time and it will also be more robustmodel.
Hope this helps