BOM Quanity on Detail Sheet

Is there any way to link the quanity of an item in a BOM tothe
detail sheet for manufacturing?SolidworksBill Of Materials
Comments 8
JB
JB 2009-02-09
No good can come of this practice. Quantities should not beshown on a manufacturing drawing for a part.

1. You can't re-use the part in some other product/assembly thatuses a different qty of said part.
2. If the qty changes, you have to issue a revision of the partdrawing.
3. If for some reason you only need to make one or two, or if youneed to make extras, the qty info on the drawing is meaningless,and cause too many or too few parts to be made.

The qty of parts manufactured should be driven by some work orderprocess, not a note on the drawing. We used to do this (not with alink, a manually entered number). We stopped due to the reasonsabove. Mainly #3.
JL
JL 2009-02-10

Josh Brady wrote:

 

No good can come of this practice. Quantities should not beshown on a manufacturing drawing for a part.



The qty of parts manufactured should be driven by some work orderprocess, not a note on the drawing. We used to do this (not with alink, a manually entered number). We stopped due to the reasonsabove. Mainly #3.

We do this all the time and it hasn't been a problem for whatwe do so this would depend on what & how you manage things.

There is no way to have SW do this automatically. What we do is tohave a custom property for both item number & quantity which islinked to our part callout on the detail drawing. We then have 2extra columns on the BOM for item number & quantity that arelinked back to the custom property in the part. These 2 columnsremain hidden until the time needed to put in the quantity &item numbers. Then we go down each row and change the qty &item numbers according to those put in by SW. Then hide the twocolumns.
JD
JD 2009-04-23
Our company's policy is to include the number on the drawingof the part. My instinct was initially that this was a badpractice, but now I see that it is appropriate for this company.The reason is that we generally create one-of-a-kind machines. Thedrawings are rarely referenced again after the machine is created.We never reuse a part between jobs. If we do, it would get a newpart # and generally treated as though it were a unique part.

Joe Dunfee
AV
AV 2009-05-25
Actually there is a way to do so parametrically - meaning that whenthe quantity changes in an assembly, it will update on the partdetail drawing. And it can be done with multiple assemblies. Seebelow:

http://www.solidworks-apac.com...rawing-parametrically/
JK
JK 2009-05-31
I design injection molds. Every part that I produce a detaildrawing for is unique to that tool. Being able to take the humanerror out of the quantity part of the detail note would be a goodthing in my opinion. Alin has an interesting solution, but it wouldnot work for me because I often have more than one item detailedper sheet. ( I use d-size sheets for my details drawings and oftenput a number of core pins or small inserts on one sheet.)

John has an idea that would work better for me. I am going to trythat and see if it works for me.
SF
SF 2009-06-01

John Kreutzberger wrote:

 

Being able to take the human error out of the quantity part ofthe detail note would be a good thing in my opinion.

Where is the "human error" in putting the quantity on theassembly BOM. Solidworks puts the quantitiy on there.

I agree with Josh- for most applications, it would be a bad idea toput the quantity in the detail drawing.
SF
SF 2009-06-01
I don't like putting the quantity on the part drawing but ifthat's what the customer wants then that's what they get or I don'tget the job.

I've detailed the same part several time just because the quantitychanged!

If someone can work out how to make an equation in a bom in anassembly bi-directional that would work. At the moment you canchange a value in a BOM and this goes back to the part file but ifyou make the cell an equation it doesn't, well I can't get it to.
SF
SF 2009-06-29
I too am in mold design and require the item detail drawingsto contain the qty in the note. Here's how I attain this:

1. Create assembly view, balloons, and BOM on your BOM sheet(s).You now have a BOM to reference.

2. When creating your detail views go to the view properties andchoose to have it linked to the BOM you created for you assemblyview.

3. Insert standard item note near view. (for us this is thedescription, material, heat treatment, surface finish and any othernotes)

4. Add a split balloon attached to the item detail view and placeballoon next to item note.

5. Set balloon properties to show Item No. and Quantity

6. Disable the leader from the balloon.

7. Group the balloon and note so that they move together, this waywhen the view moves the note/balloon move with it.

It seems like a lot of steps to attain this, but then I know thatthe quantity is coming from the software. The steps really gofairly quickly. I'm sure that a macro could be created to flythrough these as well but I'm not too skilled in that arena.